G00: Rapid Move

Overview

The G00 command instructs a rapid move to a designated coordinate position at a specified feed rate, typically used for fast positioning operations.

Command Format

Syntax: G00 X... Y... Z... E... F...
Axes X... Y... Z... E...
- Target coordinate positions to move to.
- If an axis is not specified, then no motion will occur for it.
Feed Rate
- The speed at which the movement should occur is set by parameter NC.Rapid.MaxFeedrate (see Parameter Table Parameter Table)
- If the F argument is used to reduce the feedrate, the commanded feedrate will remain in effect until G00 is no longer active
  - The feedrate for standard feeds (eg. G01, G02, G03…) will be stored when G00 becomes active and will be restored once G00 is no longer active
  - Subsequent G00 calls will use the default rapid speed unless the F argument is used again
Move End Point:
- The end point for the linear movement can be specified in either incremental (G91) or absolute (G90) values.
- In absolute programming (G90), the machine moves to a specific point in the coordinate system.
- In incremental programming (G91), the machine moves a specified distance from its current position.

Examples


									N10 G01 X0 Y0 F50

									N20 G00 X50 Y25        // moves the tool to coordinates X50, Y25 at the default rapid feedrate

									N30 G00 X50 Y25 F100   // performs the same move as above, however the `F` argument sets the feedrate to 100

									N40 G00 X60 Y60        // moves at the F100 feedrate since G00 is still active. The modal state of G00 is not affected by repeated G00 commands

									N50 X70                // moves at the F100 feedrate as a G00 move since G00 is modal 

									N60 G01 X10 Y10        // uses the F value that was active prior to the G00 call, F50

									N70 G00 X20 Y20        // uses the default rapid feedrate even though the earlier G00 call used F100 because G00 was deactivated by the G01 call

Details

By default, feed rate override does not affect G00 rapid moves
- See Feed Rate Feed Rate for more information on feed rate override behavior
Axes not specified by the G00 command do not move.

G00: Rapid Move

Overview

Command Format

Examples

Details

See Also: